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Follow the steps 1 to 24 to complete the first half of the full cad Camera tutorial, designed to enhance basic skills and enable you to create more complex designs. Then follow steps 25-48 to finish the tutorial.

 
   
 
 
  Step 1:
    Command:
From the pull down menu select: File - New - Design Maximise the screen. Then select: View - Go to - Plan

From the Workplane browser select: + to expand sketch name field. Double click on initial and change to camera top.
   
 
  Step 2:
    Command:
From the Design toolbar select: Rectangle Draw a rectangle and add horizontal and vertical sketch dimensions. Pick Select Constraints and change the dimensions to 80mm x 50mm. Change to a Trimetric view and select: View - Autoscale.
 
 
 
  Step 3:
    Command:
From the pull down menu select: Feature - Extrude Profile Set the Distance to 15mm and click on the Above workplane button. Click on the Add material button to produce a solid model that will form the basis of the camera design.
   
 
  Step 4:
    Command: From the Design toolbar select: Select faces Pick the top surface of the rectangle, (turns red), press the right mouse button and select New Sketch. Ensure Create workplane button is selected. Change the sketch name to camera lens. Select OK and sketch on the top surface.
 
 
 
  Step 5:
    Command: From the Design toolbar select: Select Circles Move the cursor over the top surface of the rectangle to the approximate position shown in the snapshot. Hold down the left mouse button and drag the mouse to extend the circle to the proportion shown, release the button to complete the circle.
   
 
  Step 6:
    Command:
From the Design toolbar select: Sketch dimension Click and hold down the left mouse button over the circumference of the circle. Drag the mouse to create a dimension. From the Design toolbar select: Select Constraints Set the diameter to 25mm
 
 
 
  Step 7:
    Command: From the pull down menu select: View - Go to - Plan From the Design toolbar select: Sketch dimension Click on the right vertical edge of the rectangle, it turns red, move the mouse over the circumference of the circle until it snaps to the centre of the circle. Drag the mouse vertically down to create the horizontal dimension.
   
 
  Step 8:
    Repeat the sequence to create the remaining dimension. Set the values to 30mm x 20mm. From the pull down menu select: View - Go to - Trimetric
 
 
 
  Step 9:
    Command:
From the pull down menu select: Feature - Extrude Profile Set the Distance to 5mm and click on the Above workplane button. Click on the Add material button to produce a solid cylinder that will form the basis of the lens design.
   
 
  Step 10:
    Command: From the pull down menu select: File - save Save the design file as camera top
 
 
 
  Step 11:
    Command: From the Design toolbar select: Select faces Pick the top surface of the cylinder, it will turn red, press the right mouse button and select New Sketch. Ensure the Create workplane button is selected and change the sketch name to lens recess. Select OK and sketch on the top surface.
   
 
  Step 12:
    Command: From the Design toolbar select: Select Circles Move the cursor over the circumference of the cylinder top until it snaps to the centre. Draw a circle from the centre of the top of the cylinder and set the diameter to 22mm.
 
 
 
  Step 13:
    Command: From the pull down menu select: Feature - Extrude Profile Set the Distance to 3mm and click on the Below workplane button. Click on the Subtract material button to produce a cylindrical recess.
   
 
  Step 14:
    Command: From the Design toolbar select: Select faces Pick the top surface of the rectangle, it will turn red, press the right mouse button and select New Sketch. Ensure the Create workplane button is selected and change the sketch name to Viewfinder. Select OK to create a new workplane and sketch on the top surface.
 
 
 
  Step 15:
    Command: From the pull down menu select: View - Go to - Plan From the Design toolbar select: Select Circles Move the cursor over the top surface to the approximate position shown in the snapshot. Draw a circle and set the diameter to 12mm.
   
 
  Step 16:
    Command: From the Design toolbar select: Sketch dimension Add a horizontal dimension of 35mm from the right side to the centre of the circle. Add a vertical dimension of 5mm from the top to the centre of the circle.
 
 
 
  Step 17:
    Command: From the pull down menu select: Feature - Extrude Profile Set the Distance to 15mm and click on the Below workplane button. Click on the Add material button to produce a cylindrical feature.
   
 
  Step 18:
    The solid model shows the result of your feature modelling in Pro/DESKTOP. In the next sequence you will create a new sketch on an existing workplane.
 
 
 
  Step 19:
    Command: From the Browser: Move your mouse over the word 'Workplane 3' in the Browser. Right click and select New Sketch from the sub menu. In the New Sketch box change the name of the sketch to viewfinder 2. You have created a new sketch on the same workplane as viewfinder 1.
   
 
  Step 20:
    Command: From the Design toolbar select: Select Circles Move the cursor over the circumference of the viewfinder cylinder until it snaps to the centre. Draw a circle from the centre of the cylinder and set the diameter to 12mm.
 
 
 
  Step 21:
    Command: From the pull down menu select: Feature - Extrude Profile Set the Distance to 2.5mm and click on the Above workplane button. Click on the Add material button to produce a cylindrical feature that represents the viewfinder.
   
 
  Step 22:
    Command: From the Design toolbar select: Select faces Pick the top surface of the viewfinder cylinder, it will turn red, press the right mouse button and select New Sketch. Change the sketch name to viewfinder window.
 
 
 
  Step 23:
    Command: From the pull down menu select: View - Go to - Plan From the Design toolbar select: Select rectangle Draw a rectangle that is constrained within the circle of the viewfinder as shown in the snapshot.
   
 
  Step 24:
    Command: From the pull down menu select: View - Zoom in Zoom a window around the detail shown in the snapshot. Add the dimensions of 6mm in height and 8mm in length. From the Design toolbar select: Line and draw a diagonal line as shown.